Machining Technology
How to Turn Titanium Alloys: Geometry, Speeds, and Coolant
Turn titanium alloys with sharp, smooth-edged tools, alloy- and feed-specific cutting speeds, and high-flow fluid that both cools and lubricates the cut....
Read Article
Broach titanium alloys with a suitable high-speed-steel or carbide tool, tooth geometry that controls rubbing and chip adhesion, and cutting speed matched to tool material. Feed per tooth is fixed during broach design, so speed is the main adjustable cutting parameter. Roughing and finishing require different rake angles, feed ranges, and wear limits, with lubrication chosen for the operation. The tabulated values apply to the listed tools and cutting conditions.
Titanium broaching can suffer from unstable accuracy, rough surfaces, short broach life, and chips that adhere firmly to the teeth. These problems are controlled through tool material, tooth geometry, cutting data, and cutting fluid.
Suitable high-speed steels include W6Mo5Cr4V2Al, W2Mo9Cr4VCo8, W12Mo3Cr4V3Co5Si, and W12Cr4VMo. The first is preferred where practical; the second performs well but costs more, while the latter grades are harder to sharpen. W12Cr4V4Mo can be used for rough broaches. YG8 and YG10H are suitable cemented carbides.
| Tool material | Rake angle | External cutting clearance | External sizing clearance | Internal cutting clearance | Internal sizing clearance | Inclination | Rake/flank Ra |
|---|---|---|---|---|---|---|---|
| HSS / carbide | 10–20° / 8–15° | 10–12° | 8–10° | 5–8° | 2–3° | 5–10° | ≤0.32 μm |
Use the lower rake-angle values for roughing and the higher values for finishing. Avoid a land on sizing teeth where possible; if one is required, keep it no wider than 0.12 mm. On slot broaches, tooth width should be at least the lower-limit slot width. Chip-curling features are similar to those used for heat-resistant superalloys.

Feed per tooth is fixed during broach design, so cutting speed is the primary controllable parameter.
| Tool material | Speed | Roughing feed per tooth | Finishing feed per tooth |
|---|---|---|---|
| HSS | 4.5–6 m/min | 0.06–0.10 mm | 0.02–0.04 mm |
| Carbide | 15–30 m/min | 0.08–0.12 mm | 0.03–0.04 mm |
A recommended mixed oil contains 60% castor oil and 40% kerosene by mass. An alternative contains 30% polyether, 30% ester oil, 30% N7 machine oil, and 10% rust-preventive and anti-oil-sludge additives. Typical wear criteria are VB ≤0.3–0.4 mm for roughing broaches and VB ≤0.15–0.2 mm for finishing broaches.
Share your drawing, material, tolerance target, or application question. Our engineering team can help review the machining route and suggest a practical next step.
Machining Technology
Turn titanium alloys with sharp, smooth-edged tools, alloy- and feed-specific cutting speeds, and high-flow fluid that both cools and lubricates the cut....
Read ArticleMachining Technology
Mill titanium with a rigid setup, strong cutting edges, and enough chip space to prevent adhesion and chip packing. Climb milling is...
Read ArticleMachining Technology
Finish-mill aluminum with a sharp, polished, high-rake cutter that resists adhesion, clears chips effectively, and uses cutting speed, feed, and shallow depth...
Read ArticleMachining Technology
The best CNC end mill depends on the cut and workpiece: square tools handle slots and profiles, ball-nose tools suit contoured surfaces,...
Read Article